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Have
you ever wanted to remove a base feature in a part but you
can't because its children will go away? Here is what
you do, open the sketch of the base feature, draw a single
straight line across the sketch in such a way that the feature
will not be able to complete the contour (Make sure you are
not using select contour functionality on your base feature
creation). Close the sketch, an error message will appear
“ The sketch has a problem that prevents its feature
from rebuilding successfully”. You will have two options,
to click “yes” “and see the problem”
or to click “no” “to exit the sketch and
rebuild anyway”. Select “no”, a “what’s
wrong” box will appear, close it. Right click on the
base feature and select “delete”. A “confirm
delete” box will appear, at the bottom of the box uncheck
the box “also delete all child features” and then
select “ yes” to complete the process. A “what’s
wrong” box will appear, close it. You will be left with
the child features and your original base feature sketch.
You may delete this sketch if it is no longer needed. If your
child feature shows a warning symbol it may now have a dangling
sketch relationship to a sketch plane. If this is the case
right click on the child feature sketch and select “edit
sketch plane”, then select an appropriate sketch plane
from the tree to place the sketch on and then select the check
mark to close.
Credit to: Ed Eaton, DiMonte Group
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